System information

SECTION FOUR - PREPARATORY FUNCTIONS (G CODES)
Single direction or one shot rapid positioning (G60)
For accurate positioning without backlash, positioning from one direction is available.
G60 X___ Y___
G60 is a one-shot G code and is used in place of G00.
Notes on Single Direction Positioning
Cutting mode (modal) (G64)
Note 1: The amount of overrun is pre-set by the machine tool builder.
Note 2: Overrun direction is not affected by mirror imaging.
Note 3: If "G00 unidirectional approach" was set by the machine tool builder, the
same positioning sequence would happen with each G00 move.
Exact stop mode (modal) (G61)
When G61 is commanded, deceleration is applied to the end point of the cutting block and in-
position is performed per block thereafter. G61 is valid until G63 (tapping mode) or G64 (cutting
mode) is commanded.
Tapping mode (modal) (G63)
When G63 is commanded, feedrate override and spindle speed override are ignored (always
regarded as 100%), and block mode and feedhold becomes invalid. G63 is valid until G61 (exact
stop mode) or G64 (cutting mode) is commanded.
G64 is the default at the beginning of each program. When G64 is commanded, deceleration
based on the angle between blocks at the end point of each block thereafter is performed, and
cutting goes on to the next block. This command is valid until G61 (exact stop mode) or G63
(tapping mode) is commanded.
Calling a program (G65 P)
G65 can also be used for calling a program. The program to be called is specified by the value
of P.
Example: *G65 P4371 (calls program #4371 and sets parameter #16 to 4371 and
parameter #7 to 65)
To pass arguments to the program, other addresses can be added to the block.
259